jisx0404 发表于 2020-7-20 19:16:35

HOLE_MILLING螺旋铣孔加底部铣园，机床报警

HOLE_MILLING螺旋铣孔加底部铣园，在加工到最后后最后一个螺旋转底部铣园时，机床报警，格式不对。
%
(Sat Jul 18 21:27:29 2020)
N0010 G40 G17 G49 G94 G00 G90
N0020 M01
N0030 (Manual Tool Change D=80.00 L=75.00 T_No.=39)
N0040 G55
N0050 G18 G00 X0.0 Z0.0 S500 M03
N0060 G43 Y479. H39
N0070 M07
N0080 Y383.
N0090 G41 G01 X36.568 Z10.333 F1200. D39
N0100 G03 X37.614 Z10.386 I1.046 K-10.333
N0110 X48. Z0.0 I0.0 K-10.386
N0120 X48. Y382. Z0.0 I-48. K0.0
N0130 X48. Y381. Z0.0 I-48. K0.0
......
......
N1010 X48. Y293. Z0.0 I-48. K0.0
N1020 X48. Y292. Z0.0 I-48. K0.0
N1030 X48. Y291. Z0.0 I-48. K0.0
N1040 X0.0 Z-48.
N1050 X-48. Z0.0 I0.0 K48.
N1060 X0.0 Z48. I48. K0.0
N1070 X48. Z0.0 I0.0 K-48.
N1080 X47.958 Z-1.999 I-48. K0.0
N1090 X37.581 Z-11.953 I-10.377 K.433
N1100 X36.106 Z-11.848 I0.0 K10.386
N1110 G40 G01 X0.0 Z0.0
N1120 G00 Y479.
N1130 M05
N1140 M09
N1150 M02
%


%
(Sat Jul 18 21:28:28 2020)
N0010 G40 G17 G49 G94 G00 G90
N0020 M01
N0030 (Manual Tool Change D=80.00 L=75.00 T_No.=39)
N0040 G55
N0050 G18 G00 X0.0 Z0.0 S500 M03
N0060 G43 Y479. H39
N0070 M07
N0080 Y293.
N0090 G41 G01 X24.147 Z9.639 F1200. D39
N0100 G03 X26.154 Z9.846 I2.007 K-9.639
N0110 X36. Z0.0 I0.0 K-9.846
N0120 X36. Y292. Z0.0 I-36. K0.0
N0130 X36. Y291. Z0.0 I-36. K0.0
.....
.....
N0460 X36. Y258. Z0.0 I-36. K0.0
N0470 X36. Y257. Z0.0 I-36. K0.0
N0480 X36. Y256. Z0.0 I-36. K0.0
N0490 X0.0 Z-36.
N0500 X-36. Z0.0 I0.0 K36.
N0510 X0.0 Z36. I36. K0.0
N0520 X36. Z0.0 I0.0 K-36.
N0530 X35.944 Z-1.999 I-36. K0.0
N0540 X26.114 Z-11.298 I-9.831 K.547
N0550 X23.575 Z-10.965 I0.0 K9.846
N0560 G40 G01 X0.0 Z0.0
N0570 G00 Y479.
N0580 M05
N0590 M09
N0600 M02
%







jisx0404 发表于 2020-7-20 19:20:29

2个程序都这样，运行到红色语句，报警，格式不对。

raokai1989 发表于 2020-7-20 19:55:35

本帖最后由 raokai1989 于 2020-7-20 19:57 编辑

后处理没有做好，X Y Z 对应I J K，你这有Z还有K同一行，矛盾

jisx0404 发表于 2020-7-20 20:07:08

raokai1989 发表于 2020-7-20 19:55
后处理没有做好，X Y Z 对应I J K，你这有Z还有K同一行，矛盾

用的侧铣G18，Y是主轴

腊月的猴子 发表于 2020-7-20 21:13:52

IJK设为非模态试试

#忘忧草# 发表于 2020-7-20 21:15:00

后处理有问题！你这个格式，报警了才是正常的

jisx0404 发表于 2020-7-20 21:20:01

N1040 X0.0 Z-48.

N0490 X0.0 Z-36.


这二句有问题，I K和最后一个螺旋相同，被省略了




修改后处理，强制输出 I K就好了

腊月的猴子 发表于 2020-7-20 21:20:24

如图所示

nei1693 发表于 2020-7-20 21:25:11

问题应该是出在N1040 X0.0 Z-48.

jisx0404 发表于 2020-7-20 21:36:03

腊月的猴子 发表于 2020-7-20 21:20
如图所示

修改了后处理
N1000 X48. Y294. Z0.0 I-48. K0.0
N1010 X48. Y293. Z0.0 I-48. K0.0
N1020 X48. Y292. Z0.0 I-48. K0.0
N1030 X48. Y291. Z0.0 I-48. K0.0
N1040 X0.0 Z-48. I-48. K0.0
N1050 X-48. Z0.0 I0.0 K48.
N1060 X0.0 Z48. I48. K0.0
N1070 X48. Z0.0 I0.0 K-48.
N1080 X47.958 Z-1.999 I-48. K0.0
N1090 X37.581 Z-11.953 I-10.377 K.433
N1100 X36.106 Z-11.848 I0.0 K10.386
N1110 G40 G01 X0.0 Z0.0
N1120 G00 Y479.
N1130 M05
N1140 M09
N1150 M02


页: [1] 2
查看完整版本: HOLE_MILLING螺旋铣孔加底部铣园，机床报警